Editing Layout Views
Edit 
3D Views (Drawing Sheet Level)
Once a layout view is created, you can use the following commands to edit the view or the part model it is associated with. These commands relate to the layout view as a single entity.
A view's individual entities (e.g., lines, arcs, circles, text, etc.) can also be edited using the standard drawing sheet tools provided but are subject to change when the view is regenerated. Refer to the tables below.
This command replaces the part model associated with a layout view. The new part will then be displayed for that view. First select the layout view to modify. Then specify the new part to reference. You can select from the default list of parts in the active file or pick the folder icon to select another VX file using the File Browser.
You cannot use this command on anything other than the base view (TOP, BOTTOM, etc..). Views with a reference view (sections, details, projection, and/or auxiliary views) cannot be used.
This command modifies the label text of a
layout view. You can also use this command to add a label to a view created
without one. Select the layout view to modify and then specify the new
label text.
This command modifies the scale factor of a layout view. The drawing sheet scale factor is ignored within layout views. The individual view's scale sets the scale factor for that view. The drawing sheet scale factor only applies to "independent" geometry that is not associated with any layout view.
Select the layout view and then enter the new scale factor.
This command edits the view attributes for existing layout views. Changes made by this command are only applied to the indicated views. The default view attributes defined in the View Attributes Form are not affected. Refer to the View Attributes Form for a description of each attribute.
Change Layout
View Component Configuration
If the referenced assembly of a layout view has multiple component configurations, use this command to change the configuration. First select the layout view to modify. Then, if the reference assembly has component configuration, select one from the list.
Activate Layout
View Part for Editing
This command activates the part model associated with a layout
view for editing. Right-click on the layout view and select Edit Part
from the Object Editor menu. The part will be activated for editing. When
you're done editing the part, pick Go up to Parent
Object
from the Tool
Bar to return to the active drawing sheet.
Use this command to regenerate layout views. This will incorporate the latest part design information into the drawing sheet. Select the views to update or middle-click to update all views. Pick Yes or No to proceed with the update. This command is located on the Tool Bar.
Optional Inputs
Regenerate unmodified views
Check this box to force the regeneration of any views whose referenced part models have not been modified.
Use this command to hide entities belonging to a particular component. Select the entities to hide. Use the Blank Swap command to view blanked entities.
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If you need to make room on a drawing sheet it is acceptable to CUT/PASTE auxiliary, folded, section and detail views to a second drawing sheet but do not erase the original definition view. Auxiliary, folded, section and detail views are dependent on their definition views. DO NOT erase these views. |
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If you need to rotate a layout view from its original position, use the right-click MOVE command (filter on ALL) not the Rotate command. Rotate works on the geometry in the view not the view itself. The position of the view is maintained after regeneration when you use MOVE not ROTATE. |
